Option File Generator HelpCycles
This option controls whether the Z value in cycle blocks is output in absolute or incremental mode. The Z value can be output several ways:
As an absolute coordinate in a cycle block
As an incremental value measured from the rapid stop point.
As an absolute incremental value measured from the rapid stop point.
Equivalent postprocessor commands:
PLABEL./OPTION,41,TO,0 $$ Output Z as absolute value (default).
PLABEL./OPTION,41,TO,1 $$ Output Z as incremental value.
PLABEL./OPTION,41,TO,2 $$ Output Z as absolute incremental value.
Some controllers automatically add a retract clearance value for the R plane. Entering a value in this box will automatically subtract this value from the value programmed as the clearance plane in the CYCLE commands.
This is a control mode in which, after performing the fixed cycle, the Z axis is returned to the initial plane. This location is identified by the Z axis location prior to a fixed cycle definition.
This is a control mode in which, after performing the fixed cycle, the Z axis is returned the the minimum clearance plane (R0). This code is identified by the R0 word in the fixed cycle. This location cannot be above the Initial Plane.
Specify the letter address to output the DEEP cycle INCR value given in the part program. Select "Disable" if this increment value is manually set at the machine tool.
Some machine tools have an option to dwell during a fixed cycle. The dwell time is specified in the cycle block using a special letter address. The LOCK option in cycle commands in the part program will generate the required dwell value. Select "Disable"if your control does not recognize this feature.
The address specified for cycle cam will be used to output the stop values for fixed cycles. The CAM option in cycle commands in the part program will generate the required cam number. Select "Disable" if your control does not recognize this feature.
Specify the letter address to output the Secondary Clearance Plane value for all canned cycles. Select "Disable" if your controller does not have a Secondary Clearance Plane. The Secondary clearance plane value c2 is given in the CYCLE command as CYCLE/--,RTRCTO,c2. Using this option, you specify if c2 is incremental or absolute from the cycle goto point. When set to absolute, you can retract to a known z-height regardless of the z-height of the drill point.
--------------------------------------------------------------------------------------------------------------------------
Option File Generator Help
Copyright (c) 2005, All Rights Reserved,
Austin N.C., 505 East Huntland Drive, Suite 480
Austin, TX 78752
www.austinnc.com